Draw a propeller in Fusion 360 for use on an overhead propeller mixer

Lilly will take you step-by-step through the process of parametrically drawing a propeller for use on a lab overhead slurry mixer. Our file is also available for download.

E. Processes

https://digitalfire.com/videos/DrawPropeller.mp4

To start, in Fusion 360, I created parameters for the hub diameter and height, the shaft diameter and the blade length, width, thickness and angle.

Step 1: Create a sketch and draw a 2-point rectangle (the size and placement do not matter).
Dimension both blade sides as blade width divided by two from the origin and set the length to blade length plus the hub diameter divided by two.

Constrain the bottom-right point horizontally parallel to the origin.
The sketch is now fully defined.
Next, I'll bevel the top left and right corners to the blade width divided by three and the bottom left one to the blade width.
Now. Let's finish the sketch and go into 3D.

Step 2: I'll extrude the whole blade upward to the blade thickness parameter.
Next, bevel the edges to the blade thickness divided by two.
Then, Y-rotate the blade to the blade angle parameter.
Finally, I'll create a circular pattern to make three blades.

For the next stage, I'll create a new sketch on the bottom plane and draw a circle, from the center, having a diameter equal to the shaft diameter parameter.
I'll make another and set its diameter to the hub diameter.
Finally, I'll finish the sketch.

Step 3: Let's make the hub.
First, extrude from two sides, both circles, to create a solid cylinder that combines with the blade to form one body. Then, adjust the height and placement of the hub.
Next, hide the body and show the second sketch, select the inner circle and extrude it upward and downward to cut the hole.
To complete, bevel the join between the blades and the hub.

Finally, print this and try it on the shaft. Likely you will have to change the shaft diameter and print again to get a tight fit.

Learn to draw a propeller or download and adjust ours

Lilly will take you step-by-step through the 3D design process of drawing a propeller. We tried many methods of doing this to finally arrive at a simple procedure that produces a flexible parametric design. Follow the full transcript as you watch. You can use the same process to create one in this or other CAD software. Our design has only nine steps yet is flexible enough to accomodate a different number of blades, changes in the blade shape, angle, thickness and size and different heights and diameters for the hub and hole. If you would like this 3D file in Fusion 360 format, it is available in the Files manager in your Insight-live.com account.

In the past, we have used Adobe Premiere for making videos. This video marks our transition to using KDenlive instead (please be patient with the rough edges until we learn this better). We are using it on Linux! It is amazing that a tool this powerful exists as free software (although they accept donations).

By Tony Hansen
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